Cut settings, also called feeds and speeds, control how your machine moves while it carves. Good cut settings give you cleaner carves, longer-lasting bits and shorter carve times.
Easel's cut settings
When you choose a bit and a material, Easel fills in its recommended cut settings for that pair. They're a good place to start.
1. Easel's default cut settings
Shows that you're using Easel's recommended settings for this bit and material.
2. Cut settings
Change any setting to enter your own values.
3. Easel community's most-used settings
The settings other makers use most for this bit and material. Click Apply to use them.
What are cut settings?
Feed rate
How fast the bit moves through the material. A higher feed rate removes more material and makes thicker chips. Too slow, and the bit rubs, dulls and overheats. Too fast, and you'll get chatter, broken bits or an overloaded machine. Feed rate doesn't affect the Z axis. You can also change it during a carve with Feed Rate Override.
Depth per pass
How deep the bit cuts each time it goes around a toolpath. For example, a 1" deep pocket at .125" per pass takes 8 passes. We don't recommend a depth per pass greater than half your bit's cutting diameter, and most settings should be lower than that. See Cut Depth and Depth Per Pass.
Spindle speed
How fast the bit spins, in RPM. Together with feed rate, it affects chip size, heat, surface finish and how long your bit lasts. Too slow causes rubbing. Too fast causes overheating or vibration.
Chip load
How much material each flute of the bit removes, measured as feed per tooth. Larger chips carry heat away, which helps with materials that melt, like acrylic, plastics and metals, but chips that are too large can break the bit. Chips that are too small make the bit rub instead of cut, which dulls it. Chips should fall onto your material or wasteboard, not float like dust.
What affects cut settings?
- Your bit: its size and type. The bit's manufacturer is the best source for settings. Bits smaller than 1/8" and engraving bits need gentler settings.
- Your material: harder materials need gentler settings. If your material isn't listed, choose one with a similar hardness. For wood, compare Janka hardness.
- Your design: detailed designs need a lower feed rate to stay accurate and avoid tear-out.
- Your machine: a rigid machine can handle faster feeds and deeper cuts. If your machine is less rigid, or your router loses power at lower speeds, keep the same feed rate and spindle speed but lower your depth per pass.
Calculating your own cut settings
Check your bit manufacturer's recommendations first. To work out settings yourself:
- Feed rate = spindle speed (RPM) × chip load × number of flutes
- Chip load = feed rate ÷ (spindle speed × number of flutes)
- Plunge rate: use a chip load of 30–50% of your feed chip load, then plunge rate = chip load × number of flutes × spindle speed.
If you don't know the chip load for your bit, .003" to .005" is a common place to start. Always test on scrap first.
Troubleshooting
| What you see | Likely cause | Try this |
|---|---|---|
| Dust instead of chips | Feed rate too low or spindle speed too high | Raise feed rate, lower spindle speed |
| Long, stringy chips | Feed rate too high or chips not clearing | Lower feed rate; clear chips with air or an upcut bit |
| Burn marks or smoke | Spindle speed too high or feed rate too low | Lower spindle speed, raise feed rate |
| Bit breaks or dulls quickly | Feed rate too high, depth per pass too deep, or machine not rigid | Lower feed rate and depth per pass; check the bit and your clamping |
| Chatter or vibration | Bit flexing, loose material, or feed and speed out of balance | Lower depth per pass, raise feed rate slightly, clamp material firmly, shorten bit stick-out |
| Tear-out or fuzzy edges in wood | Wrong bit type or direction | Use a downcut or compression bit; raise spindle speed slightly |
| Dull or discolored metal chips | Too much heat or a dull bit | Lower spindle speed, use coolant, replace the bit |
| Ridges or poor finish | Feed rate too high, bit flexing, or worn bit | Lower feed rate and step over; check or replace the bit |
| Squealing or whining | Spindle speed too high or bit rubbing | Lower spindle speed, raise feed rate |
If your spindle stalls or the bit gets stuck, start by lowering your depth per pass. Stalls can also come from a router without enough power, chips packing into the cut, loose clamping or a dull bit.